Article Contents
Constant Lead Threading Cycle Introduction
Tapered screws and scroll threads in addition to equal lead straight threads can be cut by using a G32 command.
The spindle speed is read from the position coder on the spindle in real time and converted to a cutting feedrate for feed-per minute mode, which is used to move the tool.
| You may be interested also: |
| “Siemens CNC Turning | CYCLE97 | Thread Cutting” |
G32 Code Format
| G32 IP_ F_; |
Parameters
| IP_: End point |
| F _: Lead of the long axis (always radius programming) |
G32 Cycle Examples
Example – 1 – Straight Threading Example
The following values are used in programming :
Thread lead :4mm
δ1=3mm
δ2=1.5mm
Depth of cut :1mm (cut twice)
(Metric input, diameter programming)
G00 U-62.0 ;
G32 W-74.5 F4.0 ;
G00 U62.0 ;
W74.5 ;
U-64.0 ;
(For the second cut, cut 1mm more)
G32 W-74.5 ;
G00 U64.0 ;
W74.5 ;
Example – 2 – Tapered Threading Example
The following values are used in programming :
Thread lead : 3.5mm in the direction of the Z axis
δ1=2mm
δ2=1mm
Cutting depth in the X axis direction is 1mm (cut twice)
(Metric input, diameter programming)
G00 X 12.0 Z72.0 ;
G32 X 41.0 Z29.0 F3.5 ;
G00 X 50.0 ;
Z 72.0 ;
X 10.0 ;
(Cut 1mm more for the second cut)
G32 X 39.0 Z29.0 ;
G00 X 50.0 ;
Z 72.0 ;
Need to More?
Our volunteers have worked together and carefully prepared the articles published here in their native language without using machine translation. You can search the entire site for more information on the subject. You can start a discussion on CNCarea.com forums and join us to get support, ask questions, improve a published article or give your opinion.
